. .
Page 2 of 3 FirstFirst 123 LastLast
  1. #11
    Thanks

    from the error message it appears the controller hijacks the G31 as well so not much difference in G31 & M31.

    I will try again today but not holding out much hope, CSL support is so slow as to be annoying as well, beginning to regret the purchase a bit :(

    Yes, analog servo drives 10-0-10v control.

  2. #12
    Quote Originally Posted by matt-b2 View Post
    Hi,

    Has anyone had any luck getting Mach3 with a CSMIO/IP-M controller to work with a probe properly?

    The probe I'm using works fine, G31 and CS Lab's M31 macro (http://en.cs-lab.eu/technical-suppor...native-to-g31/) both work in that both cause my CNC router to move until either the probe triggers or the specified distance is reached.

    What does not work is, variables 2000-2002 (which are supposed to contain the X, Y & Z coordinates of the probe event) do not update properly. For some reason, variable 2000 updates consistently with the Y coordinate (when it is supposed to contain the X coordinate), but variables 2001 and 2002 either contain zero or nonsensical values.

    Mach3 and the CSMIO/IP-M firmware are both up-to-date (R3.043.066 and V2.91 respectively). I have the probe tip diameter set on Mach3's Settings screen.

    Ideas/suggestions much appreciated.

    Matt.
    Dear Matt,

    I use also the CNC controller CSMIO IP-M together with Mach 3 in the newest version and the last CSMIO firmware.
    For tool probing I got always the Y value for var(2002). I contacted CS-Lab support for help but the answer was that I do not understand the macro.
    I was shure to use the macro right and tried everything to find the fault. So I checked the connection of the motors and the channels.
    That was the solution and I changed my wiring.
    I connected the x-axis to Channel 0, the y-axis to channel 1 and the z-axis to channel 3. After that I tried the tool length measurement again and got the
    right values.

    I hope this information will help you.

    Phil

  3. #13
    Yes XYZ is channel 0-1-2 and so on.

    I have my probe working well now - the secret is to allow some time in the macro so pad it with "Sleep(100)" lines after a DRO update etc also it ONLY works with soft limits turned off - i just made the macro turn limits off then on when the move was made.

    Its going well now.

  4. #14
    Yes, that's a bit of a gotcha - that "sleep" after a DRO update is absolutely vital, as is the "while moving" loop so you wait for the machine to reach target position before carrying out the next action. However, my version works fine with soft limits, so not sure what's going on there.

  5. #15
    Yes, its only a 0.1s wait and it needs going after every DRO update, i also padded it after every DRO read, plus the totally essential while-ismoving loop on ANY call that creates movement of an axis.

    Doing this likely added 5s to the macro run time but thats no bother if its what it takes to make it work 100%

    The soft limits thing i'm going to play with again - it seems very version dependant so now I have the timings sorted, ill try leaving it on and see what occurs. CSLABS said they had never heard of it BUT they always run v022 so that may be why.

  6. #16
    gixi's Avatar
    Lives in Bucuresti, Romania. Last Activity: 20-08-2019 Has been a member for 2-3 years. Has a total post count of 2.
    Hello everybody !

    My DIY router is 99% finished but setting the Z probe proves to be a pain in the … .
    After 3 weeks of reading, testing and so on, I manage to write a script based on M31 example from CSMIO site.
    All seems to work fine except the fact that I could not reset the z value to zero in Mach3 screen. I give a try to G92 (it’s working) but there are too many warnings of how I should use this g code.
    Any suggestion to solve this problem will be much appreciated.

    This is part of my code:
    If(GetUserDRO(1510) = 1) Then
    Message("M31 Probe hit.")
    Call SetDro (2, ZOffset)
    Code "(Z zeroed)"
    Sleep(1000)
    Code "G0 Z20 F50"
    Code "G4 P10"
    Code "G0 Z-10 F50" (Touch plate has 10mm)

  7. #17
    Chaz's Avatar
    Lives in Ickenham, West London, United Kingdom. Last Activity: 3 Weeks Ago Has been a member for 9-10 years. Has a total post count of 1,600. Received thanks 110 times, giving thanks to others 69 times.
    Quote Originally Posted by gixi View Post
    Hello everybody !

    My DIY router is 99% finished but setting the Z probe proves to be a pain in the … .
    After 3 weeks of reading, testing and so on, I manage to write a script based on M31 example from CSMIO site.
    All seems to work fine except the fact that I could not reset the z value to zero in Mach3 screen. I give a try to G92 (it’s working) but there are too many warnings of how I should use this g code.
    Any suggestion to solve this problem will be much appreciated.

    This is part of my code:
    If(GetUserDRO(1510) = 1) Then
    Message("M31 Probe hit.")
    Call SetDro (2, ZOffset)
    Code "(Z zeroed)"
    Sleep(1000)
    Code "G0 Z20 F50"
    Code "G4 P10"
    Code "G0 Z-10 F50" (Touch plate has 10mm)
    Get Ger's Screenset 2010 and just his probe routines.

  8. #18
    Quote Originally Posted by gixi View Post
    Hello everybody !

    My DIY router is 99% finished but setting the Z probe proves to be a pain in the … .
    After 3 weeks of reading, testing and so on, I manage to write a script based on M31 example from CSMIO site.
    All seems to work fine except the fact that I could not reset the z value to zero in Mach3 screen. I give a try to G92 (it’s working) but there are too many warnings of how I should use this g code.
    Any suggestion to solve this problem will be much appreciated.

    This is part of my code:
    If(GetUserDRO(1510) = 1) Then
    Message("M31 Probe hit.")
    Call SetDro (2, ZOffset)
    Code "(Z zeroed)"
    Sleep(1000)
    Code "G0 Z20 F50"
    Code "G4 P10"
    Code "G0 Z-10 F50" (Touch plate has 10mm)
    Her is one of my probe macros, there might be something in there to help, I tend to annotate a lot ;) Its for CSMIO IP/A under Mach3


    Sub Main()
    '***X- Probing Macro
    '***Written by and for DD Metal Products Ltd 2018
    '***Metric units only in use
    '***Using CSLABS Controller M31 macro code
    '***Axis scaling not expected or handled
    '***Probe offset must be calibrated at "Slow Feedrate" value and set in "Probe Tip Dia" DRO first
    '***Probe Z axis position is set by user first to correct height
    '***Probe Y position must be within the value set in "Max Distance" DRO

    Dim FeedFast, FeedSlow
    Dim ProbeOffset
    Dim MaxDistance
    Dim ZClearance
    Dim StepBack
    Dim X_SENSE
    Dim Y_SENSE
    Dim Z_SENSE

    '***Load Variables From Screen DROs
    FeedFast = GetUserDRO(1821)
    Sleep (100)
    FeedSlow = GetUserDRO(1822)
    Sleep (100)
    MaxDistance = GetUserDRO(1823)
    Sleep (100)
    ProbeOffset = GetUserDRO(1829)
    Sleep (100)
    ZClearance = GetUserDRO(1830)
    Sleep (100)
    StepBack = GetUserDRO(1824)
    Sleep (100)

    '***Error checks
    If GetOemLed(16)<>0 Then '***Check for machine coordinates setting
    Message "Please Change To Working Coordinates"
    Exit Sub
    End If

    If GetOemLed(825)<>0 Then '***Probe is not connected or cable broken
    Message "Probe Connection Error"
    Exit Sub
    End If

    If StepBack=0 Then '***Stepback not set
    Message "Please enter a step-back value"
    Exit Sub
    End If

    If ABS(GetOEMDRO(85))<ZClearance Then '***Z axis too high for retract
    Message "Spindle too high for clearance move"
    Exit Sub
    End If

    '***Start Probing
    Message "Probing In X- Direction"
    Sleep (100)

    Code "F" & Feedfast
    Sleep (100)

    SetUserDRO(1511, 0-MaxDistance) '***X Axis
    Sleep (100)
    SetUserDRO(1512, 0) '***Y Axis
    Sleep (100)
    SetUserDRO(1513, 0) '***Z Axis
    Sleep (100)

    Call ProbeSurface()

    X_SENSE = GetVar(2000)
    Sleep (100)

    '***Step back
    Code "G91 G0 X" & StepBack
    While IsMoving()
    Sleep(50)
    Wend

    Code "F" & FeedSlow
    Sleep (100)

    SetUserDRO(1511, 0-(StepBack+2)) '***X Axis
    Sleep (100)
    SetUserDRO(1512, 0) '***Y Axis
    Sleep (100)
    SetUserDRO(1513, 0) '***Z Axis
    Sleep (100)

    Call ProbeSurface()

    X_SENSE = GetVar(2000)
    Sleep (100)

    '***Step back
    Code "G91 G0 X" & StepBack
    While IsMoving()
    Sleep(50)
    Wend

    '***Raise the spindle to clear part
    Code "G91 G0 Z" & ZClearance
    While IsMoving()
    Sleep(50)
    Wend

    '***Move Y axis to edge and zero the DRO
    Code "G90 G0 X" & X_SENSE - ProbeOffset
    While IsMoving()
    Sleep(50)
    Wend
    SetOemDRO(800,0)
    Sleep(100)

    '***Retract the spindle fully
    'Code "G53 G0 Z0"
    'While IsMoving()
    ' Sleep(50)
    'Wend

    '***Make sure we are in G90 again
    Code "G90"

    Message "X- Probing Complete"

    End Sub







    Sub ProbeSurface()

    NotifyPlugins(10103)

    SetUserDRO(1510, 0)
    While(GetUserDRO(1510) = 0)
    Sleep(50)
    NotifyPlugins(10104)
    Wend

    If(GetUserDRO(1510) = 2) Then '***Probing error - no detection in distance = abort
    Message "Probing Error - No Surface Found"
    End
    End If

    End Sub

  9. #19
    Quote Originally Posted by Chaz View Post
    Get Ger's Screenset 2010 and just his probe routines.
    I've had several users that had issues with CS Labs controllers and the 2010 Screenset.
    Gerry
    ______________________________________________
    UCCNC 2022 Screenset

    Mach3 2010 Screenset

    JointCAM - CAM for Woodworking Joints

  10. #20
    Chaz's Avatar
    Lives in Ickenham, West London, United Kingdom. Last Activity: 3 Weeks Ago Has been a member for 9-10 years. Has a total post count of 1,600. Received thanks 110 times, giving thanks to others 69 times.
    Quote Originally Posted by Ger21 View Post
    I've had several users that had issues with CS Labs controllers and the 2010 Screenset.
    Mine works OK. Ive not use my machine for a while now but had no issues with it.

Page 2 of 3 FirstFirst 123 LastLast

Thread Information

Users Browsing this Thread

There are currently 1 users browsing this thread. (0 members and 1 guests)

Similar Threads

  1. csmio/ip-m z probe
    By charlieuk in forum CS-Lab (CSMIO)
    Replies: 0
    Last Post: 16-09-2017, 09:49 AM
  2. mach3 csmio ips errors
    By Web Goblin in forum Artsoft Mach (3 & 4)
    Replies: 7
    Last Post: 07-01-2017, 10:47 PM
  3. Mach3 oem buttons with CSMIO-IP/S
    By Web Goblin in forum Artsoft Mach (3 & 4)
    Replies: 2
    Last Post: 07-11-2016, 07:14 AM
  4. CSMIO-M Tool Probe Connection - +24v to earth
    By Noplace in forum CS-Lab (CSMIO)
    Replies: 1
    Last Post: 10-04-2016, 09:17 PM
  5. Weird problem - stepped/staged deceleration on Huanyang 2.2kw Spindle
    By glynster in forum Spindles & Drive Motors
    Replies: 0
    Last Post: 25-01-2016, 01:39 PM

Bookmarks

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •