. .
Page 8 of 36 FirstFirst ... 67891018 ... LastLast
  1. #71
    Chaz's Avatar
    Lives in Ickenham, West London, United Kingdom. Last Activity: 2 Weeks Ago Has been a member for 9-10 years. Has a total post count of 1,600. Received thanks 110 times, giving thanks to others 69 times.
    Quote Originally Posted by routercnc View Post
    OK, more updates. To finish off the info on the bed rail supports, here is the little jig I made up to hold the bosses in place:
    Attachment 20182

    Here it is in position:
    Attachment 20183

    It uses 6mm shoulder bolts to give a good reference position and picks up off the inner tapped hole already there. This holds the boss in just the right place for welding. It's now ready for welding - just need to catch my friend with the welder in the next few days or so. This is bolt down the supported rail which obviously uses a pair of bolts on either side of the flange.
    I've also taken the opportunity to spot out the holes for a profiled rail (i.e down the middle) to make a future upgrade much easier to do.


    Next up are the end plates which hold the motor mounting plates. Starting with a nice skimmed off the sacrificial board:
    Attachment 20184

    Then setting up:
    Attachment 20185
    (note that I've scribbled down the X, Y, Z coord of the workoffset on the drawing - I always write them down in case of power failure)

    I'm making a mirrored pair here. A few holes, and a large pocket in the middle of each one. You can drill and screw through the waste first, but and I'll talk you through my approach on the large cutout as it worked quite well as an alternative. This is all to avoid those terrible tool witness marks from tabs.

    1) Use an inside profile with a 1mm offset (remaining stock on the side wall) WITH TABS.
    Attachment 20205

    2) Then drill through the tabs with a cordless drill to remove the waste:
    Attachment 20187

    3) Manually jog the machine to remove most of the tabs (not critical to get all of it)
    Attachment 20188

    4) Clean up profile pass to remove the last 1mm. I do this in 2 stages as this is what works for my machine. 1st cleanup 3mm DOC, 0.9mm WOC, final cut full DOC, 0.1mm WOC.

    Gives this surface finish:
    Attachment 20189

    Then bolting down, removing clamps, and onto the profile cut:
    Attachment 20190

    Same approach as above using a rough cut leaving 1mm stock, then semi-finish 3mm DOC, 0.9mm WOC, and finish full DOC, 0.1mm WOC. A stiffer/better machine might do the finish in one pass. I'm also limited to 6mm max cutter on ER11 collet. Good finish anyway:
    Attachment 20191

    Mirror part cut the same way, then some holes tapped and surface cleaned up:
    Attachment 20192

    The bearing end plates were done in the same way:
    Attachment 20193

    Then onto the bearing holders:
    Attachment 20194

    Attachment 20195

    They will be a light press fit:
    Attachment 20196

    Second one made:
    Attachment 20197

    Trial fit onto the bearing plates:
    Attachment 20198

    This allows the ballscrew end bearing position to be fine tuned when setting up.
    __________________

    Moving away from the X axis and onto the Y axis - the belt tensioning system progresses. Turned some standoffs to hold the adjustable belt guide bearings:
    Attachment 20199

    Attachment 20200
    ______________________________

    Looking ahead I need to turn down the end of one of the ballscrews. Made these 2 bits to hold it in the lathe. First is a protective collar to stop the jaws damaging the ballscrew:
    Attachment 20201

    Made it by boring a hole into some round stock on the lathe.
    Then machined a hex onto some round stock:
    Attachment 20202

    Then used the hex to give 120 degree spacing to machine the 3 slots. Don't have a hex collet block which would have done the job!
    Attachment 20208

    Then back to the lathe to part it off:
    Attachment 20203

    Then to support the end of the ballscrew as it passed out of the headstock a spider/collar to fit inside the lathe spindle bore and hold the ballscrew. The ballnut is then 'tightened' up against it. Copied the whole idea off Youtube so should be OK!
    Attachment 20204
    Very awesome, loving the work you are doing.

  2. The Following User Says Thank You to Chaz For This Useful Post:


  3. #72
    Coming along nice mate keep it rolling.

  4. #73
    Some quality surface finishes there, nice :)

  5. #74
    Clive S's Avatar
    Lives in Marple Stockport, United Kingdom. Last Activity: 13 Hours Ago Forum Superstar, has done so much to help others, they deserve a medal. Has been a member for 9-10 years. Has a total post count of 3,333. Received thanks 618 times, giving thanks to others 78 times. Made a monetary donation to the upkeep of the community. Is a beta tester for Machinists Network features.
    Very nice build log I follow it very carefully its a credit to you. You could also call it tips and tricks
    ..Clive
    The more you know, The better you know, How little you know

  6. #75
    Well, thank you all for the kind words of support. Means a lot, especially coming from the seasoned machinists on here.

    I've re-read some of my latest posts and have realised that they paint a glowing picture where everything I do is perfect and works first time. This is misleading for the novices out there so I've decided to include things that went wrong for posts where there is something of interest. Readers have just as much to learn from things that work for me, as well as what not to do!

    So here are some things that did not go so well / areas for improvement.

    1. When making the bearing holder I'd broken my last good 6mm carbide the day before and a new one had not arrived. So I was stuck with an old blunt one. To give it a fighting chance at the pocket I chain cnc drilled out some of the material using a 3mm drill bit:
    Click image for larger version. 

Name:	IMG_5636.jpg 
Views:	237 
Size:	277.1 KB 
ID:	20218

    But the carbide bit made a nasty noise and was not happy. I switched over to a 3mm carbide and carefully cut it out. You can see the evidence of the 6mm blunt carbide on the top surface:
    Click image for larger version. 

Name:	IMG_5637.jpg 
Views:	229 
Size:	291.1 KB 
ID:	20219

    I had another look through my draws and found a single flute 6mm carbide which I've used for plastic. I cut the outer profile out with that one, plus all of the second part.

    2. The 'second part' in the photo was actually the third part:
    Click image for larger version. 

Name:	IMG_5645.jpg 
Views:	216 
Size:	245.9 KB 
ID:	20222
    The real second part went on the scrap pile. On the drawing I'd called for a 36mm bore to take the bearing. After the roughing cut (~1.0mm under) I offered up the bearing and it almost fitted. Scratched my head and measured the bearing and it was actually 35mm. Using Vectric 2D you cannot leave stock etc so the quickest fix was to frig the tool diameter (e.g. telling the software that dia is '8mm' whereas it is actually 6mm gives you 1.0mm stock). Rather than re-draw the part, CAM, etc. I did a quick calc and frigged the tool. Bearing dropped in the new bore with 0.5mm clearance all round. Useless! Thought about making a sleeve, but 1.5 hours later had a replacement made with the proper size bore.

    3. The radius on some of the corners is exactly 3mm. This is bad practice with a 6mm bit as there is suddenly a large tool engagement which leaves a witness mark. Better to go with 3.1 or 3.2 if radius is cosmetic. Look at the bottom right inner radius to see the slight chatter. Not a big deal, but one to be aware of.
    Click image for larger version. 

Name:	IMG_5643.jpg 
Views:	244 
Size:	244.5 KB 
ID:	20221

    4. Vectric cut 2D does not have lead in/out. This means there is a tool witness mark at the start / end of the finishing cut. You can help with a ramp in, but the exit goes straight up past the side of the work leaving a groove/scratch. Look at the wall near the top left screw:
    Click image for larger version. 

Name:	IMG_5639.jpg 
Views:	228 
Size:	391.4 KB 
ID:	20220

    Let me know if the bad stuff is as interesting as the good stuff and I'll include that too . . .
    Building a CNC machine to make a better one since 2010 . . .
    MK1 (1st photo), MK2, MK3, MK4

  7. The Following User Says Thank You to routercnc For This Useful Post:


  8. #76
    It's all interesting!!!....good to see the good as well as the bad...if you want to see ugly ill show some of my stuff 😁

    Sent from my HUAWEI VNS-L31 using Tapatalk
    Neil...

    Build log...here

  9. The Following User Says Thank You to njhussey For This Useful Post:


  10. #77
    Quote Originally Posted by njhussey View Post
    It's all interesting!!!....good to see the good as well as the bad...
    Ditto!
    And this novice (little old me) finds your posts very easy and a real pleasure to follow.
    Many Thanks, routercnc!
    Last edited by AndyGuid; 05-01-2017 at 01:34 AM.

  11. #78
    Brief update. Next up were the plates which hold those bearing holders . . .

    Setting it out, drilling out some of the holes and pockets:
    Click image for larger version. 

Name:	IMG_5625.jpg 
Views:	204 
Size:	234.3 KB 
ID:	20360

    Then bolting down through the holes so I can machine around the outside:
    Click image for larger version. 

Name:	IMG_5627.jpg 
Views:	196 
Size:	337.0 KB 
ID:	20361

    Quick trial fit to make sure all is well:
    Click image for larger version. 

Name:	IMG_5646.jpg 
Views:	201 
Size:	206.5 KB 
ID:	20362

    Went OK but broke a bit when I called for an 11 mm DOC instead of 1 mm in the CAM and didn't stop the machine in time.

    I couldn't fit the standard ballscrew blocks in under the end of the gantry so am making my own. There will be 4 in total, 2 each side to allow me to pre-load one ballnut against the other to remove the 50 microns or so of ballscrew backlash. Here are 2 of the blocks, with 2 more on order:

    Click image for larger version. 

Name:	IMG_5630.jpg 
Views:	221 
Size:	148.4 KB 
ID:	20363

    I need to machine 45 degree chamfers on the top of the block but don't have an Engineer's vee block
    Click image for larger version. 

Name:	vee.jpg 
Views:	212 
Size:	36.9 KB 
ID:	20364

    So I machined up a jig with a 45 degree notch:
    Click image for larger version. 

Name:	IMG_5677.jpg 
Views:	218 
Size:	421.1 KB 
ID:	20365

    Here it is in position to show the idea (tabs yet to be filed off):
    Click image for larger version. 

Name:	IMG_5679.jpg 
Views:	224 
Size:	190.3 KB 
ID:	20366

    Then the blocks had to be squared up. There are lots of videos and info on how to do this on the internet so I won't repeat in detail. Great example here:
    https://www.youtube.com/watch?v=tW8HNAlUXxU

    In the photo below you can see a raw block (right) and the squared up block in the jaws (left). The brass rod is used whenever an un-machined face is against the clamping jaw otherwise it won't sit flat against the fixed jaw. The deadblow hammer is to make sure the part is seated in the vice.
    Click image for larger version. 

Name:	IMG_5681.jpg 
Views:	240 
Size:	332.4 KB 
ID:	20367

    Once squared up I set it up against a backstop (actually a parallel doubling up as a stop - must make something better !). It is now ready to have the details machined into the end such as the ballnut mounting holes. I can't machine the large clearance hole right through the centre because the part is 50 mm long. Even machining both sides its a bit too deep. So my plan is to bore a precise 20 diameter pocket in the end (say 10mm deep), then set it up on the 4-jaw, indicate on that bore to centre it, then bore it out.
    Click image for larger version. 

Name:	IMG_5682.jpg 
Views:	235 
Size:	363.4 KB 
ID:	20368
    Building a CNC machine to make a better one since 2010 . . .
    MK1 (1st photo), MK2, MK3, MK4

  12. #79
    Very nice build and documentation of the process. Thanks!

    Quote Originally Posted by routercnc View Post
    4. Vectric cut 2D does not have lead in/out. This means there is a tool witness mark at the start / end of the finishing cut. You can help with a ramp in, but the exit goes straight up past the side of the work leaving a groove/scratch. Look at the wall near the top left screw:
    You could split the finishing contour line and add radii in CAD if you are a perfectionist

  13. #80
    Quote Originally Posted by paulus.v View Post
    Very nice build and documentation of the process. Thanks!



    You could split the finishing contour line and add radii in CAD if you are a perfectionist
    Interesting thought Paulus. I see where you are coming from but would I end up with an open contour? I'll check it out but I think Cut2D only accepts closed contours. Longer term I'm transitioning to Fusion 360 where these more advanced options are standard practice.
    Building a CNC machine to make a better one since 2010 . . .
    MK1 (1st photo), MK2, MK3, MK4

Page 8 of 36 FirstFirst ... 67891018 ... LastLast

Thread Information

Users Browsing this Thread

There are currently 2 users browsing this thread. (0 members and 2 guests)

Bookmarks

Posting Permissions

  • You may not post new threads
  • You may not post replies
  • You may not post attachments
  • You may not edit your posts
  •