4.3 mm holes, 20 mm deep

**m_c** · 07-08-2017

Having a quick look at the catalogue, 11.170 are a high helix version of what I use, which will help with chip clearance.

I'm not sure about what settings are in Huanyang VFDs, but the one you want to alter is for current. IIRC there is some setting whereby you can limit the current once a certain frequency is reached, but it's been along time since I read a manual. There will reach a frequency, where current will be limited by the maximum power available, which a good VFD will handle without any problem, but I'm not sure how a Huanyang will.

11.170 has a cutting speed of 40-65m/s (2961 to 4811rpm for 4.3mm diameter), with a suggested DOC of about 0.13 to 0.2mm per revolution. At 12500rpm, even at 0.1mm DOC, you're looking at 1250mm/m feed rate.
Running the figures through my spreadsheet, that equates to a cutting torque of 0.5 to 0.8Nm.

The postage cost from phantom is high if you're only ordering a couple drills, but I normally order over £50 at a time, so it's not so big an issue.

**Chaz** · 07-08-2017

Originally Posted by m_c

Having a quick look at the catalogue, 11.170 are a high helix version of what I use, which will help with chip clearance.

I'm not sure about what settings are in Huanyang VFDs, but the one you want to alter is for current. IIRC there is some setting whereby you can limit the current once a certain frequency is reached, but it's been along time since I read a manual. There will reach a frequency, where current will be limited by the maximum power available, which a good VFD will handle without any problem, but I'm not sure how a Huanyang will.

11.170 has a cutting speed of 40-65m/s (2961 to 4811rpm for 4.3mm diameter), with a suggested DOC of about 0.13 to 0.2mm per revolution. At 12500rpm, even at 0.1mm DOC, you're looking at 1250mm/m feed rate.
Running the figures through my spreadsheet, that equates to a cutting torque of 0.5 to 0.8Nm.

The postage cost from phantom is high if you're only ordering a couple drills, but I normally order over £50 at a time, so it's not so big an issue.

Thanks. Ive checked some of the settings of the VFD online, Ill need to check tonight to see if its set right.

So clearly 75mm/min is nowhere near the right amount. Ive noted other machines that have high speed spindles just simply plunge and drill in what looks to be a millisecond. These are not always with spindle/tool through coolant. Clearly at 75mm/min I was just rubbing and dulling the tip.

I may order some of the German endmills and donate them for breaking / testing. Must be a way to get this right. In hindsight, I should have tested this on some scrap metal before doing it on the actual part. That said, small piece of alu, not the end of the world, the part will still work, just looks a bit crappy where the broken drill moved around in the hole.

**routercnc** · 08-08-2017

Hi Chaz,

If it helps - in the line boring video I posted recently you can see 3 mm holes being peck drilled (with full retract to clear the chip) at ~12,000 rpm. Can't remember the feed - maybe 300 mm/min? Drill bit is plain HSS.

You can see the chip fly out each time, and a dab of oil keeps it running smoothly. Starts at 0:32
https://www.youtube.com/watch?v=sYhDtuqzf2I&t=6s

Been using this method for some time and it works well.

**Chaz** · 08-08-2017

Originally Posted by routercnc

Hi Chaz,

If it helps - in the line boring video I posted recently you can see 3 mm holes being peck drilled (with full retract to clear the chip) at ~12,000 rpm. Can't remember the feed - maybe 300 mm/min? Drill bit is plain HSS.

You can see the chip fly out each time, and a dab of oil keeps it running smoothly. Starts at 0:32
https://www.youtube.com/watch?v=sYhDtuqzf2I&t=6s

Been using this method for some time and it works well.

Thanks.

I did some checking last night. My VFD's current looks to be set correctly.

There is an auto compensation value for increased torque demand. Set to default of 2% but can go to 10%. That's now changed.

There are also some parameter values between PD005 and PD010 which allow different torque curves. I *think* default is a constant curve, there is an option to go for what's called high torque where it provides better torque at lower speeds. This will help a bit, Ill lower the speed and see. Clearly the feedrate of what I was doing was too slow too.

Also, what oil do people use? Anything specific or just 2 in 1 oil? Ive got big container of VG220 Mobil oil that I got with one of my ballscrew / rail orders. Would that work and is it better than trying to spray WD40?

**Chaz** · 08-08-2017

Ok, pushed up the VFD power a bit, it doesnt seem to like this but has worked.

I used a 4mm drillbit for the 4.x mm holes and the bolts fit well, no need for the slight oversize IMHO. Redid the failed 5mm holes, done.

12500 rpm, 0.25 depth, full retract, 500mm/min plunge.

I did have a problem with Thor which cost me about 2 hours, the bearing nut came loose and caused problems. I had heard something but didnt investigate it earlier, no damage done, phew.